G-Wizard Calculator:
Fast, Easy, Reliable Feeds and Speeds


Join 100,000+ CNC'ers!  Get our latest blog posts delivered straight to your email inbox once a week for free. Plus, we’ll give you access to some great CNC reference materials including:

  • Our Big List of over 200 CNC Tips and Techniques
  • Our Free GCode Programming Basics Course
  • And more!


GCode is Complicated
G-Wizard Makes it Easy

Ultimate Guide to Selecting Toolholders for Milling

Dec 2, 2013   //   by Bob Warfield   //   Beginner, Blog, FeedsSpeeds, Manufacturing, Products, Techniques  //  11 Comments

Over the years, we’ve written a lot of articles about toolholders for milling machines.  They’re an important topic and I frequently get questions about them.  Recently, I found myself having to visit multiple CNCCookbook articles to answer a question and decided it was time to get all the information into one article along with refreshing the research and seeing what new information I could add.  In addition, I wanted to make as much of the information tabular as possible to make it easy to refer to.  Here’s what I came up with:

Best Milling Toolholders

For each toolholder type, there are multiple rows with scores from 1 to 4, where a higher score is better.   4 is the best score and 1 is the worst.

Let’s go over each row and what it means.


To achieve precision, you’ll need low runout and repeatability for the tool holder.  The Weldon-style set screw holder has the lowest precision because set screws against a flat on the tool shank will push the tool off center and because you can’t guarantee repeatability since a slight rotation of the shank will change the exact point at which the setscrews engage.


This is simply a measure of how many shank sizes a single toolholder of the type can accommodate.  In theory, greater versatility means you’ll need fewer toolholders.

Ease of Use

This is a measure of how easy it is to setup a cutter in the toolholder or take it back out.  Nothing could be easier than using a set screw holder–just stick a cutter in and tighten the set screws.  The Shrink-Fit holder requires the use of a heat shrink machine to do anything.  In the middle are toolholders that require proper assembly torque.

This is a good time to put in a plug for proper ER collet chuck torquing.  For best performance, they require a lot more torque than most machinists realize.  That torque goes to keeping the tool clamped so it won’t pull out and to making the whole assembly rigid so it resists vibration and chatter.

When you hear a machinist talking about having an endmill slip in an ER collet chuck, you have to wonder two things:

– How clean was the chuck and cutter shank when they were tightened together? The slightest residue of oil or cutting fluid can rapidly reduce the collet’s holding power.

– How much torque was used to tighten the collet nut?

Consider the following torque specs from Technik USA:

Collet Nut Type Collets I.D. Collets I.D.
OVER 1/16″ (2mm) UNDER 1/16″ (2mm)
ER 16 slotted 42 ft/lbs 30 ft/lbs
ER 16 hex 42 ft/lbs 30 ft/lbs
ER 20 slotted 59 ft/lbs 24 ft/lbs
ER 20 hex 59 ft/lbs 24 ft/lbs
ER 25 slotted 77 ft/lbs 77 ft/lbs
ER 25 mini nut 25 ft/lbs 25 ft/lbs
ER 32 slotted 100 ft/lbs 100 ft/lbs
ER 40 slotted 130 ft/lbs 130 ft/lbs

Are you torquing your ER32 collets to 100 ft/lbs? That’s a bunch more than a lot of folks expect going on feel alone.

Whether you use a torque wrench or not, and Technik as well as others make appropriate adapters, make sure you’ve at least got a nice wrench for your chuck. The single pin spanners are the worst for me when I have to apply a lot of torque. In addition, you’re going to need a way to solidly mount your collet chuck while you tighten the nut. Bench fixtures are the most helpful for this task.


This is a measure of how much maintenance is needed to keep the toolholder performing to spec.  Set screw holders are dead easy as are shrink-fit–no moving parts.  Collet chucks and milling chucks need to be kept clean and torqued to proper specs.

High Speed

This row scores the suitability of different toolholders for higher spindle speeds.  “High” starts in the 8000-10,000 rpm range and the primary requirement is the ability to balance the toolholder well.  Less mass in the toolholder will also help because the less mass that’s spinning, the less vibration at a given level of balance.

Working well with high speed spindles is one of the biggest reasons to invest in fancier toolholders.

Surface Finish and Roughing

These two categories get into suitability for task.  For surface finish, we need to keep the modal stiffness high to resist vibration.   For roughing finish, we want high dynamic stiffness to resist chatter under varying loads, rpms, and frequencies, and we want strong clamping on the tool to resist the higher forces of roughing.


Cost is near and dear to everyone’s pocketbook, and the costs vary quite a lot between these various toolholders

Best Application

Drumroll please, this is the one we’ve been waiting for:  what’s the best situation for each toolholder type?

This bears recapping:

–  For your absolute highest MRR milling and drilling applications, consider a Side Lock or Weldon Shank-style toolholder.  We’re talking big indexable tooling for the most part, not solid endmills.

–  For mid-sized milling and drilling, consider a Milling Chuck.  This is your largest solid endmills and twist drills, say 3/4 to 1″ and up.  Also consider these when you have chatter problems on your big tooling using a Side Lock holder.

–  For lighter milling and drilling, consider an ER collet chuck.  Anything 3/4″ or under makes sense.

–  For high rpm applications, consider shrink fit toolholders.

Obviously there is some gray area of overlap in each of these cases, but this should serve as a good starting point for toolholder selection.


Like what you read on CNCCookbook?

Join 100,000+ CNC'ers!  Get our latest blog posts delivered straight to your email inbox once a week for free. Plus, we’ll give you access to some great CNC reference materials including:

  • Our Big List of over 200 CNC Tips and Techniques
  • Our Free GCode Programming Basics Course
  • And more!

Just enter your name and email address below:

Full Name
Email *
100% Privacy: We will never Spam you!

Ultimate Guide to Selecting Toolholders for Milling
Rate this post


  • What about DA collets?

    how do they compare to ER collets? They seem a little sturdier to me, since they are generally longer.

  • 13, I thought about including DA collets, but the sources I consulted were not fond of them. Try Parlec, for example:

    Given good ER solutions, didn’t seem worthwhile to make the table bigger.

  • Hi Bob, I’m new to this and to your site. I’m curious to know where Sherline Endmill holders would fit. Would you classify those as sidelock holders?

    • Yes Eric, those are definitely side-lock holders. I wouldn’t think you’d want to use them on a Sherline. The high rpms and small cutters won’t like the runout very much. The Sherline page mentions preferring the collets. That’s more like an R8-style collet than a 5C though. If you can find a small enough 5C collet setup that works with the Sherline’s Morse Taper, that would be ideal.



  • Thanks., I learned something new. I enjoy your site.

  • I’m not sure I know what a “milling chuck” is. I have some Jacobs 14N chucks in my tool holders. Is that what the column heading means? The article’s comment about mid sized milling (3/4″ – 1″) would take a big chuck.
    Thanks for a great site and great tools and organizing a great community.

    • Hi Lynn. Milling chucks are not related to Jacobs chucks at all:

      Nikken invented milling chucks and will tell you more than you wanted to know (LOL):

      RE the Jacobs chucks, a lot of machinists don’t use them, preferring ER collet chucks. They have a lot of runout and it isn’t especially advantageous to change bits in one if you have a toolchanger.

  • Bob,

    ER collets are ok and all, but to define them as the most accuracte collet is incorrect. The very common TG style and several other derivative styles exceed the ER by a good margin in clamping force and runout. The ER are simply available nearly everywhere and for cheap, not that that is good!


  • Reason we prefer ERs over TGs are the size of the clamping nut. The TG has a large square profile typically and so is a little harder to get coolant to and to clear obstructions. Though not as strong as a regular nut, the ER mini nut for example has a very small profile. I second Bob, we never use any Albrecht or Jacobs chucks in our day to day as they will not transmit anywhere near the torque the ERs or TG will.

  • […] Short of much fancier and more expensive solutions, ER Collets are one of the best toolholding systems available. Consider this comparison from our Ultimate Guide to Selecting Toolholders for Milling: […]

Leave a comment


Do you want to be a better CNC'er in 37 Seconds?

Get Better Tool Life, Surface Finish, and Material Removal Rates Fast.

It's that easy. You can install and get results in a matter of minutes.


Start Now, It's Free!



  GW Calculator

  GW Editor



  Deals and Steals

CNC Blog








     Feeds and Speeds

     G-Code Tutorial

     CNC Machining & Manufacturing

     DIY CNC Cookbook

     CNC Dictionary

CNC Projects


     Machinist's Search


     Online Groups


     Reference Data


     CNC Dictionary


     Tool Brands


     Hall of Fame

     Organization: Soon!





     Our History

     Privacy Policy

All material © 2016, CNCCookbook, Inc.